Genmitsu PROVerXL 4030¶

About¶

Specification¶

Title	Spec
Working area	400 x 300 x 110mm
Control Board Compatibility	GRBL 1.1h
Spindle	300W 6A, 12,000 RPM
Max speed	2000mm/min
Accuracy	0.1 mm
Overall Machine Size	641 x 755.5 x 580mm
Machine Weight	26kg
Collet (in package)	1/8” Shank

Test¶

CAM: Mods ¶

Attention

See Adjust MODS’ g-code for this machine first (below)

read SVG
- select SVG file -> 30x30_40x40mm.svg
convert SVG image
- ** Check ** image size: 39.980 x 39.980 (mm)
set PCB defaults
- mill outline (1/32) -> Click to set
mill raster 2D
- calculate -> Click to make path -> Download .nc file
- view -> Click to see Path
  Download: SVG image.nc

G-gode sender: gSender ¶

Installation

Set up Software¶

Note

Do not install if you have the current macOS Mojave 10.14 or later. macOS Mojave 10.14 (released in October 2018) includes a CH34x driver by Apple. If both Apple’s and the OEM driver are installed, they will create conflicting non-functional serial ports.

Install CH340 Driver
Download setting file gSender-settings-Genmitsu PROVerXL-4030.json.zip
Gear icon(right top) -> Clock to open Setting
- General -> Settings -> Import Settingds
- Import Setting gSender-settings-Genmitsu PROVerXL-4030.json

Connect PROVerXL 4030 and power ON
Connect to Machine -> Unrecognized devices -> /dev/tty.wchusbserial1440

Set up Machine¶

Click to Run Homing

Danger

Machine Move to home position (right up)
Make sure you are SAFE ! Work area is clear!!

Jog Control
- Home (Machine origin)
  - X: 0 (Right)
  - Y: 0 (Back)
  - X: 0 (Up)
- Jog
  - X: “ X- ” to move Left
  - Y: “ Y- ” to move Forword
  - Z: “ Z- ” to move Down
- Keyboard short cut
  - X: shift + right/left
  - Y: shift + up/down
  - Z: shift + pageup/pagedown

Tool setting
- Use 2 Wrenches
  - No.13 : hold top
  - No.17 : loose/tight Collet holder

Move to Material
- Use Jog control to your material(left-down)

Z-touch
- Use paper to touch the tool on the paper surface
- move one more -0.1mm down to reach the material surface

Work ZERO
- Click Zero All to Work origin (X0,Y0,Z0)

Load File¶

Click Load File and open SVG image.nc

Start milling¶

Click Start Job to run

Milled¶

From this result, 30mm design

30x30mm	X	Y
SVG	29.52	29.57
PNG	29.50	29.55
Ave	29.51	29.56
30/Ave	1.016605	1.014885

Adjust G-code Parameters¶

Ref

Open Console (right-down)

grblで設定できる項目の詳細（1.1対応）

Type and Enter

$$

This is default settings

client $$
$0=10 (Step pulse time, μs)
$1=255 (Step idle delay, ms)
$2=0 (Step pulse invert, mask)
$3=0 (Step direction invert, mask)
$4=0 (Invert step enable pin, boolean)
$5=0 (Invert limit pins, boolean)
$6=0 (Invert probe pin, boolean)
$10=3 (Status report options, mask)
$11=0.010 (Junction deviation, mm)
$12=0.002 (Arc tolerance, mm)
$13=0 (Report in inches, boolean)
$20=0 (Soft limits enable, boolean)
$21=1 (Hard limits enable, boolean)
$22=1 (Homing cycle enable, boolean)
$23=0 (Homing direction invert, mask)
$24=25.000 (Homing locate feed rate, mm/min)
$25=500.000 (Homing search seek rate, mm/min)
$26=250 (Homing switch debounce delay, ms)
$27=3.000 (Homing switch pull-off distance, mm)
$30=10000 (Maximum spindle speed, rpm)
$31=0 (Minimum spindle speed, rpm)
$32=0 (Laser-mode enabled as spindle, boolean)
$100=160.000 (X-axis travel resolution, step/mm)
$101=160.000 (Y-axis travel resolution, step/mm)
$102=160.000 (Z-axis travel resolution, step/mm)
$110=2000.000 (X-axis maximum rate, mm/min)
$111=2000.000 (Y-axis maximum rate, mm/min)
$112=2000.000 (Z-axis maximum rate, mm/min)
$120=300.000 (X-axis acceleration, mm/sec^2)
$121=300.000 (Y-axis acceleration, mm/sec^2)
$122=300.000 (Z-axis acceleration, mm/sec^2)
$130=420.000 (X-axis maximum travel, mm)
$131=310.000 (Y-axis maximum travel, mm)
$132=110.000 (Z-axis maximum travel, mm)
ok

Look at these three parameters

$100=160.000 (X-axis travel resolution, step/mm)
$101=160.000 (Y-axis travel resolution, step/mm)
$102=160.000 (Z-axis travel resolution, step/mm)

X and Y axis¶

I need to change these numbers

30x30mm	X	Y
SVG	29.52	29.57
PNG	29.50	29.55
Ave	29.51	29.56
30/Ave	1.016605	1.014885
travel resolution 160.000*30/Ave [step/mm]	162.657	162.382

To set numbers, simply type and enter, one by one

$100=162.657

$101=162.382

To check to be saved

client $$
.
.
$100=162.657 (X-axis travel resolution, step/mm)
$101=162.382 (Y-axis travel resolution, step/mm)
$102=160.000 (Z-axis travel resolution, step/mm)
.

SVG 30x30mm	X	Y
Test_1 travel resolution [step/mm]	162.657	162.382
Result_1 [mm]	30.03	30.05
Test_2	162.495	162.119
Result_2	29.91	29.99
Test_3	162.984	162.173
Result_3	30.00	30.00-29.99

This is the setting from Test_3

$100=162.984 (X-axis travel resolution, step/mm)
$101=162.173 (Y-axis travel resolution, step/mm)
$102=160.000 (Z-axis travel resolution, step/mm)

Z axis¶

Height Gauge	Value	Diff
Before	7.60	0
After 10mm down	6.61	-9.99

This is the setting from Test (no change)

$102=160.000 (Z-axis travel resolution, step/mm)

Surfacing¶

Tool¶

3/4” = 19.05mm
Change Collet to 3/4”

Click Surfacing (Top-Center)

Dimensions: size of a spoiled board
Router Bit Diameter 19 mm
Start Position
- left-down
Genetate G-code -> Run on Main Visualizer
Click Start job to start surfacing

Attention

This is very DUSTY process!!

Adjust MODS’ g-code for this machine¶

mods

Compare G-code form png and from SVG

Note

PNG’s G04 P1 or SVG’s G04 P1000 need to be commented out for this machine, otherwise machine will stop on this line.

Attention

T1M06 may be also need to be commented out. This happened when wchusbserial1440 did not appear in the device list to connect. Possibly CH340 driver may not be installed successfully.

30x30_40x40mm_96dpi.png.nc	SVG image.nc	Meanig
%	%	% Signals start
G17	G17	G17 Select X-Y plane
G21	G21	G21 Metric units
G40	G40	G40 Cancel cutter compensation
G49	G49	G49 Cancel cutter
G54	G54	G54 Set Datum
G80	G80	G80 Cancel cycles
G90	G90	G90 Absolute programming
G94	G94	G94 Per minute feed
T1M06	T1M06	T1 Tool Number, M06 Tool Change
F150.0000	F150.0000	F Defines feed rate
S11000	S11000	S Defines speed
G00Z2.0000	G00Z2.0000	G00 Positioning at rapid travel Z2.0000
M03	M03	M03 Spindle on clockwise
G04 P1	G04 P1000	G04 Dwell P[ms]
G00Z2.0000	G00Z2.0000
G00X5.3263Y4.7937Z2.0000	G00X5.0324Y4.8037Z2.0000
G01Z-0.7989 F150.0000	G01Z-0.7117 F150.0000
F150.0000	F150.0000
G01X5.3263Y5.0600Z-0.7989	G01X5.0324Y4.8291Z-0.7117
G01X4.7937Y5.5926Z-0.7989	G01X4.9816Y4.8291Z-0.7117
G01X4.7937Y34.6208Z-0.7989	G01X4.8545Y4.9561Z-0.7117
G01X5.8589Y35.1534Z-0.7989	G01X4.8037Y5.1086Z-0.7117
G01X34.6208Y35.1534Z-0.7989	G01X4.8037Y34.9472Z-0.7117
G01X35.1534Y34.0882Z-0.7989	G01X4.9561Y35.1251Z-0.7117
G01X35.1534Y5.3263Z-0.7989	G01X5.1086Y35.1759Z-0.7117
G01X34.0882Y4.7937Z-0.7989	G01X34.9472Y35.1759Z-0.7117
G01X5.3263Y4.7937Z-0.7989	G01X35.1251Y35.0235Z-0.7117
G00Z2.0000	G01X35.1759Y34.8710Z-0.7117
G1X0Y0Z0	G01X35.1759Y5.0324Z-0.7117
M05	G01X35.0235Y4.8545Z-0.7117
M30	G01X34.8710Y4.8037Z-0.7117
%	G01X5.0324Y4.8037Z-0.7117
	G00Z2.0000
	M05	M05 Spindle Stop
	M30	M30 Program end, return to start
	%

Ref. G-gode, M-code, T1M06, G04, G54, %

Edit path to G-code module¶

Comment out G04 P1000 and

//
// local functions
//
function make_path() {
   var dx = 25.4*mod.width/mod.dpi
   var cut_speed = parseFloat(mod.cutspeed.value)
   var plunge_speed = parseFloat(mod.plungespeed.value)
   var jog_height = parseFloat(mod.jogheight.value)
   var nx = mod.width
   var scale = dx/(nx-1)
   var in_mm_scale = 1
   if (mod.formatInch.checked) {
      dx /= 25.4
      scale /= 25.4
      cut_speed /= 25.4
      plunge_speed /= 25.4
      jog_height /= 25.4
      }
   if (mod.unitMinutes.checked) {
      cut_speed *= 60
      plunge_speed *= 60
      }
   var spindle_speed = parseFloat(mod.spindlespeed.value)
   var tool = parseInt(mod.tool.value)
   str = "%\n" // tape start
   str += "G17\n" // xy plane
   if (mod.formatInch.checked)
      str += "G20\n" // inches
   if (mod.formatMm.checked)
      str += "G21\n" // mm
   str += "G40\n" // cancel tool radius compensation
   str += "G49\n" // cancel tool length compensation
   str += "G54\n" // coordinate system 1
   str += "G80\n" // cancel canned cycles
   str += "G90\n" // absolute coordinates
   str += "G94\n" // feed/minute units
   //str += "T"+tool+"M06\n" // tool selection, tool change..................comment out
   str += "F"+cut_speed.toFixed(4)+"\n" // feed rate
   str += "S"+spindle_speed+"\n" // spindle speed
   if (mod.coolanton.checked)
      str += "M08\n" // coolant on
   str += "G00Z"+jog_height.toFixed(4)+"\n" // move up before starting spindle
   str += "M03\n" // spindle on clockwise
   //str += "G04 P1000\n" // give spindle 1 second to spin up................comment out
   //str += "G04 P1\n" // give spindle 1 Millisecond to spin up..............comment out

save local program¶

Download local program¶

mill_2D_PCB	PNG	SVG
html	png.html	svg.html
txt	png.txt	svg.txt

open local program¶

html
- Double Click mill_2D_PCB_svg.html (work in local PC)
text
- Open mods (MIT server)
- left click -> program -> open local program -> mill_2D_PCB_svg.txt -> open

line Test¶

1/64¶

V-bit¶

Cutting Edge Diameter 0.2mm
30 Degrees

Depth of Cut	Width of Cut
0.1	0.25359
0.2	0.30718
0.3	0.36077

Ref. calculator width-of-cut of a “V” shaped cutting tool

Depth = 0.2mm

Adjust G-code Parameters 2022/4/25¶

Design, g-code, milling¶

Easel

Test_0¶

$$
...
$100=162.984 (X-axis travel resolution, step/mm)
$101=162.173 (Y-axis travel resolution, step/mm)

Tests and Result¶

	test_0	test_1	test_2
X-axis(L-R)
$100	162.984	161.290	161.403
length	101.05	99.93	100.02 ok
Y-axis(Up-Dw)
$101	162.173	161.174	161.126
length	100.62	100.03	100.01 ok

Parameters from test_2 are good to use

$$
...
$100=161.403 (X-axis travel resolution, step/mm)
$101=161.126 (Y-axis travel resolution, step/mm)

Last update: December 23, 2023

Genmitsu PROVerXL 4030¶

About¶

Specification¶

Test¶

Design: Fusion360 ¶

Export: Shaper Utilities ¶

CAM: Mods ¶

G-gode sender: gSender ¶

Set up Software¶

Set up Machine¶

Load File¶

Start milling¶

Milled¶

Adjust G-code Parameters¶

X and Y axis¶

Z axis¶

Surfacing¶

Tool¶

Adjust MODS’ g-code for this machine¶

Edit path to G-code module¶

save local program¶

Download local program¶

open local program¶

line Test¶

1/64¶

V-bit¶

Adjust G-code Parameters 2022/4/25¶

Design, g-code, milling¶

Test_0¶

Tests and Result¶

Genmitsu PROVerXL 4030¶

About¶

Specification¶

Test¶

Design: Fusion360¶

Export: Shaper Utilities¶

CAM: Mods¶

G-gode sender: gSender¶

Set up Software¶

Set up Machine¶

Load File¶

Start milling¶

Milled¶

Adjust G-code Parameters¶

X and Y axis¶

Z axis¶

Surfacing¶

Tool¶

Adjust MODS’ g-code for this machine¶

Edit path to G-code module¶

save local program¶

Download local program¶

open local program¶

line Test¶

1/64¶

V-bit¶

Adjust G-code Parameters 2022/4/25¶

Design, g-code, milling¶

Test_0¶

Tests and Result¶

Design: Fusion360 ¶

Export: Shaper Utilities ¶

CAM: Mods ¶

G-gode sender: gSender ¶